Load Step: CLOAD
In the CLOAD-Force dialog, define the *CLOAD card for dofs 1 through 3 and the CLOAD-Moment for dofs 4 through 6.
In Abaqus, *CLOAD can have degrees of freedom (dof) 1 through 6. In Engineering Solutions, concentrated loads with dofs 1 through 3 are called force and those with dofs 4 through 6 are called moments. The force and moments are two separate entities that are defined from separate panels. Their graphical displays are also different. As a result, the Step Manager has two distinct tree options for *CLOAD: CLOAD-Force and CLOAD-Moment.
Open Concentrated loads in the tree, select CLOAD-Force or CLOAD-Moment, and a load collector from the Load collector table to open the corresponding dialog in the right-most section of the Load Step window.
It is recommended that you do not use both CLOAD–Force and CLOAD-Moment in the same load collector in Engineering Solutions. If you need to use both types of *CLOAD in the same STEP, define each type in a separate load collector and add them to the same load step.
Load Step: CLOAD: Define Tab
In the Define tab, define *CLOAD (force or moment) cards on individual nodes or geometry (points). You can also define the *CLOAD on node sets.
- Nodes or geometry
- Node sets
The layout of the Define tab changes based on your selection.
Define CLOAD-Force/Moment On: Nodes or Geometry
Use the Define CLOAD-Force/Moment on: Nodes or geometry option to define *CLOAD (force or moment) on individual nodes or geometry.
The concentrated loads created on nodes have special graphical display in HyperMesh. Loads created on geometric entities such as surfaces, lines, or points are automatically mapped to FEA mesh on export. They can also be mapped using the Map Loads on Geometry button.
Button | Action |
---|---|
Define from 'Forces'/'Moments' Panel | Opens the Engineering Solutions Forces or Moments panel
to create/update a CLOAD. To create a CLOAD on nodes, go to the create subpanel, select nodes using the switch, pick the desired nodes from Engineering Solutions graphics, select the global/local system, select a vector, input a magnitude, and click create. To create a CLOAD
on geometry, go to the create subpanel, select
points using the switch, pick the
desired geometry from Engineering Solutions graphics,
select the global/local system, select a vector, input a
magnitude, and click create.
Note:
|
Map Loads on geometry | Opens the Engineering Solutions Loads on Geom panel to
map loads on geometry to FEA mesh entities. Click
Map loads to map all geometric
loads in the current load collector to FEA entities.
Note:
|
Define CLOAD-Force/Moment On: Node Sets
The Define CLOAD-Force/Moment on: Node sets option defines CLOAD on node sets.
Column | Description |
---|---|
Nodeset | The name of the node sets. Node sets are added or removed using → or ←, respectively. |
Comp_x | The component in x direction. The x-direction indicates dof 1 for force and dof 4 for moment. |
Comp_y | The component in y direction. The y-direction indicates dof 2 for force and dof 5 for moment. |
Comp_z | The component in z direction. The x-direction indicates dof 3 for force and dof 6 for moment. |
Magnitude | The magnitude. This column is non-editable. The magnitude is calculated based on the Comp_x, Comp_y, and Comp_z defined for each node set when you click Update. |
Load Id | The ID of the load collector. |
For tips on entering information and navigating in the Define tab, see Step Manager Tab Environment.
Button | Action |
---|---|
Review Set | Reviews the selected node sets by highlighting them in the Engineering Solutions graphics. Right-click Review to clear the review selections. |
Create/Edit Set.. | Opens the Entity Sets panel in Engineering Solutions. When you finish creating/editing the set, click return. The Step Manager is updated with the new set appearing in the element set list. |
Display/Review from panel | Opens the appropriate Engineering Solutions panel. Use the review button to expand the loads and constraints on the sets for visualization purposes. |
→ | Add the selected node set from the drop-down menu to the data line table on the right. |
← | Delete the selected node set from the data line table. |
Define by vector | Opens the Engineering Solutionsvector selector panel. Pick a vector and click proceed. This vector is used to define the Comp_x, Comp_y, Comp_z, and Magnitude of the CLOAD for the selected node set. |
Create/Edit vector | Opens the Vectors panel in Engineering Solutions. When you finish creating/editing the vector, click return. |
Review | Creates special review forces or moments in Engineering Solutions graphics for the selected node set. These review forces or moments take into consideration the *TRANSFORM cards that may be associated with nodes in the node set. Right-click Review to clear the special review loads and highlighting. |
Update | Updates the Engineering Solutions database with the data lines defined in the table. By default, Engineering Solutions does not display loads defined with sets. |
Load Step: CLOAD: Delete Tab
In the Delete tab, delete *CLOAD and other loads.
Option | Description |
---|---|
All loads in current collector | The Delete button deletes all the loads from the current load collector. |
All 'CLOAD' in current collector | The Delete button deletes only *CLOAD loads from the current load collector. |
By selection | The Pick Loads button opens the Engineering Solutions
load selector panel. Pick the loads you want to delete and click
proceed. The corresponding Reset button resets the selected loads. The Delete button deletes the selected loads. |
Load Step: CLOAD: Parameter Tab
In the Parameter tab, define optional parameters for the *CLOAD card.
The supported parameters are: Amplitude, OP, Load Case, Cyclic Mode, Follower, and Region Type.
Click Update to activate the optional parameter selection in the Engineering Solutions database.